Sunking PCB

Heavy Copper PCB Current Capacity: Trace Width, Temperature Rise and the Finished Copper Cross-Section

Design Guide2026-11-04Sunking Circuits Technical Team
Heavy Copper PCB Current Capacity: Trace Width, Temperature Rise and the Finished Copper Cross-Section

Designers usually pick heavy copper for a simple reason: the current is high, and 1 oz traces would be either too wide to fit or too hot. They look up a current chart or open a calculator, enter current and allowed temperature rise, get a width, and write "outer layers 4 oz" on the drawing.

The calculator assumes an ideal rectangular conductor in an assumed environment. The fabricator delivers something else: a trapezoid narrower at the top than at the base after etching, a finished thickness made of base foil plus plating, a width with a tolerance, and a stackup with fixed thickness and copper distribution. On a 1 oz board the gap is negligible. On heavy copper it often is not.

What a current chart actually answers

A current chart answers one question: how much does a conductor of a given cross-sectional area heat up at a given current, on a given board in a given environment? The current reference method is IPC-2152. Unlike the older IPC-2221 curves, it treats board thickness, laminate thermal conductivity, nearby copper planes, and internal versus external placement as variables that change the result.

Two consequences follow:

  1. The input is cross-sectional area, not ounce weight. Ounces describe foil weight per area; you still need the real thickness and the real width to get the area.
  2. The same cross-section heats differently on different boards. Nearby planes, a thicker board and more copper all spread heat faster.

So "how many amps through 4 oz at 5 mm wide" has no single answer. It depends on the finished cross-section and on the board itself.

Cross-section: where nominal and finished differ

Calculation assumesWhat heavy copper actually hasEffect
Rectangle, top width = base widthEtch undercut gives a trapezoid, narrower on topReal area is smaller than width × thickness
Thickness = nominal oz conversionOuter layers: base foil + plated copper; inner layers: foil onlySame oz callout, different finished thickness
Width = design valueWidth carries a manufacturing toleranceArea moves with width
Isolated conductorSolder mask, prepreg fill and copper on nearby layersHeat path differs from the chart

The thicker the copper, the larger the difference between top and base width. Fabricators apply etch compensation to the artwork so the finished width meets the design value; how that is reviewed is covered in heavy copper etch compensation review. Compensation fixes the width. The trapezoid remains. If you calculate area as top width × nominal thickness, you overestimate current capacity.

SKPCB's trace width tolerance is ±20% (PCB-TRACE-TOL). For a power trace with little thermal margin, calculate with the width at the low end of the tolerance, not the nominal value.

Treat inner and outer layers separately

"4 oz" on an inner layer and on an outer layer are not the same thing:

  • Outer layers usually reach finished thickness through thinner base foil plus plating, and plating uniformity depends on the pattern. The drawing should state whether the callout means finished copper or base foil.
  • Inner layers use foil of the stated weight with no plating on top, but are surrounded by prepreg, so heat can only leave through dielectric and adjacent layers.

One finding of the IPC-2152 work is that in a typical multilayer board with nearby planes, internal conductors do not necessarily run hotter than external ones. It depends on the stackup. Do not apply old rules such as "make inner traces twice as wide"; calculate with the real stackup or test.

Choosing between copper weight tiers, and what each tier tightens, is covered in 3 oz vs 6 oz vs 12 oz copper weight tiers and is not repeated here.

Environment: why the same cross-section heats differently

Besides cross-section, temperature rise depends on where the heat goes. Common variables on heavy copper boards:

  • Adjacent copper planes: a large copper area one or two layers away spreads heat sideways and lowers the rise noticeably.
  • Board thickness and layer count: more thickness and more copper layers add heat capacity and conduction paths. SKPCB builds boards up to 6.0 mm thick (PCB-THICK).
  • Copper area and layout: an isolated narrow trace and a wide pour behave very differently at the same current. Parallel high-current traces heat each other.
  • Mounting and airflow: a sealed enclosure, a heatsink contact or forced air are all outside the chart.
  • Vias and transitions: current changing layers passes through holes, and the plated barrel area is often smaller than the trace area, creating a local hot spot. The plated-hole aspect ratio limit is 10:1 (PCB-AR), so thicker boards need larger holes.

Most of these are design decisions. The fabricator builds what the drawing says, so a temperature requirement cannot be reduced to a trace width; the operating conditions must be stated with it.

How to state it for the fabricator

When current requirements go into fabrication documents, state them in this form rather than as a single ounce value:

  1. Definition of finished copper: say whether the value is finished copper or base foil, for inner and outer layers separately. Where a minimum matters, give it, e.g. "outer finished copper ≥ X µm", with X taken from your calculation.
  2. Critical power net list: name each high-current net, its layer, rated current and allowed temperature rise, and mark them on the drawing. Engineering review then checks compensation, spacing and hole copper on those nets first.
  3. Minimum width at the low tolerance limit: subtract the width tolerance during calculation, not at CAM.
  4. Stackup and copper distribution: give the full stackup with copper and dielectric thickness per layer. Prepreg fill and copper balance on heavy layers affect manufacturability; see heavy copper multilayer mixed-weight stackup.
  5. Layer-change via requirements: specify the number of vias, hole size and hole copper at high-current transitions.
  6. Verification method: state whether cross-sections are required to confirm the conductor geometry, and who measures temperature rise under what conditions.

How to verify cross-section and temperature rise

The fabricator can verify cross-section. A metallographic microsection of a finished board or same-lot coupon shows top width, base width, copper thickness and hole copper directly, so you can check the real conductor against your assumptions. Where to cut and how to read it is covered in PCB microsection analysis.

Temperature rise can only be measured in realistic conditions. It depends on assembled component heat, enclosure and airflow, so it is a product-level test, usually run by the designer or a third-party lab on a powered prototype. The bare-board fabricator guarantees geometry and continuity: SKPCB runs 100% electrical test on every order (Q-ETEST) to confirm there are no opens or shorts. Electrical test does not measure temperature rise.

Writing these two items into the documents separately avoids the situation where the board was built to drawing, the temperature rise is out, and nobody can tell which side owns the problem.

SKPCB heavy copper capability

SKPCB's maximum copper weight is above 12 oz, with 16 oz and 18 oz in production (PCB-COPPER). Product scope is on heavy copper PCB and thick copper PCB. For current-driven projects, upload the stackup, critical power net list and temperature conditions through quote; engineering review checks width and compensation against the finished cross-section.

Summary

The current a heavy copper PCB can carry is set by the real cross-section and the thermal environment together. The nominal ounce weight is only the starting point: undercut makes the conductor a trapezoid, inner and outer layers finish at different thicknesses, width has a tolerance, and stackup and mounting change the rise. Put the finished copper definition, critical nets, low-limit width, stackup and verification method into the documents, and the calculation will describe the board you receive.

FAQ

Q: How many amps can a 4 oz trace of a given width carry?

A: There is no single number. It depends on finished cross-section, allowed rise, board thickness, nearby planes and mounting. Calculate with the IPC-2152 method using the real stackup and low-limit width, then verify on a prototype.

Q: Why does width × thickness overestimate the area?

A: Heavy copper etching undercuts the conductor, leaving a trapezoid narrower on top. Using top or nominal width times nominal thickness overstates area and capacity.

Q: Do inner-layer traces always run hotter than outer ones?

A: No. In multilayer boards with nearby planes, heat from an inner conductor passes through the dielectric to the plane and spreads. The answer depends on the stackup.

Q: Should the drawing specify base foil or finished copper?

A: Current calculations use finished copper, so specify finished copper, with a minimum where needed, for inner and outer layers separately.

Q: Can the fabricator test temperature rise?

A: The fabricator confirms geometry by microsection and continuity by electrical test. Temperature rise depends on assembly, component heat and enclosure, so it is measured on the prototype.

Q: What matters at high-current layer transitions?

A: Plated barrel area is often smaller than the trace area and becomes a hot spot. Specify via count, hole size and hole copper separately, and respect the aspect ratio limit for the board thickness.

Related links

Need the current and thermal budget checked?

Copper weight, trace width and temperature rise have to be solved together. Tell us your current and ambient targets and we will advise copper weight with manufacturable width/spacing.